Skip to content
Engineering Bible

Results appear as you type. Use the arrow keys to move through them and Enter to open one.

Popular

↑ ↓ moveEnter openEsc close

Bend allowance calculator (sheet metal flat length)

Sheet metal bend allowance, bend deduction, outside setback and flat length for one or many bends, from thickness, radius, angle and K-factor.

Units
Sheet 0.06 in thick bent 90° round an inside radius of 0.06 in: bend allowance 0.12488 in.BA 0.12488 ininside radius 0.06 int 0.06 inBend allowance 0.12488 inOutside setback 0.12 in, bend deduction 0.11512 in90° bend, K = 0.325Dashed: the neutral axis, which keeps its lengthThickness and radius to scale; legs shortened
Drawn for the default inputs. It redraws as you change them.

Results are estimates. They do not replace the governing code, class or flag requirements, or a check by a competent person. Report a problem

Introduction

When sheet metal bends, the outside stretches and the inside compresses. One layer in between, the neutral axis, keeps its length. The bend allowance is the length of that layer through the bend. It sets how long the flat blank must be. A 90° bend in 2 mm steel over a 2 mm radius uses 4.16 mm of material along the neutral axis.

This calculator gives the bend allowance, the outside setback and the bend deduction of one bend. It then adds up the flat length of a part with any number of bends from its outside dimensions. It suggests a K-factor by DIN 6935 or takes your own. It is for sheet metal designers, press brake operators and anyone laying out a blank.

Formulas

One bend, with the bend angle θ in radians:

BA = θ × (R + K × T)
OSSB = tan(θ/2) × (R + T)
BD = 2 × OSSB − BA

Flat length from outside dimensions (legs measured to the mould lines):

L_flat = Σ legs − Σ BD

K-factor suggested by DIN 6935:

k = 0.65 + 0.5 × log10(R/T)   for R/T < 5,   k = 1 above
K = k / 2
  • T — sheet thickness; R — inside bend radius; θ — bend angle (90° for an L)
  • K — position of the neutral axis from the inside surface, as a fraction of T
  • BA — bend allowance; OSSB — outside setback; BD — bend deduction

Assumptions and limitations

  • The K-factor depends on the material, the tooling and the ratio R/T. The DIN formula gives 0.325 at R = T and 0.5 from R = 5T. A test bend and a measured blank give the best value for your shop.
  • Leg lengths are outside dimensions. Each one runs to the point where the outside surfaces of two legs would meet.
  • The bend angle is the angle the sheet turns through, not the angle left between the legs. A 90° L-bracket has a bend angle of 90°, and a 120° opening has a bend angle of 60°.
  • In air bending, the inside radius follows the die opening, not the punch radius. Use the radius the part really gets.
  • Springback and thinning in the bend are not modelled.

Worked example

A U-channel is 30 × 50 × 30 mm outside, in 2 mm steel, with a 2 mm inside radius. What blank length is needed?

  1. R/T = 1, so DIN 6935 gives k = 0.65 and K = 0.325.
  2. Bend allowance: π/2 × (2 + 0.325 × 2) = 4.16 mm.
  3. Outside setback: tan 45° × (2 + 2) = 4 mm.
  4. Bend deduction: 2 × 4 − 4.16 = 3.84 mm.
  5. Flat length: 30 + 50 + 30 − 2 × 3.84 = 102.33 mm.

With K = 0.44 the blank would be 103.05 mm, 0.72 mm longer.

Sheet 2 mm thick bent 90° round an inside radius of 2 mm: bend allowance 4.1626 mm.
The worked example, drawn by the same code as the live drawing above.

Common cases

One 90° bend in common sheet and plate thicknesses, with the K-factor suggested by DIN 6935 from R/T. Subtract the bend deduction once per bend from the sum of the outside dimensions to get the blank length.

CaseThickness (mm)Inside radius (mm)K-factorBend allowance (mm)Bend deduction (mm)
0.8 mm sheet, inside radius 0.8 mm0.80.80.3251.6651.535
1 mm sheet, inside radius 1 mm110.3252.08131.9187
1.5 mm sheet, inside radius 1.5 mm1.51.50.3253.1222.878
2 mm sheet, inside radius 2 mm220.3254.16263.8374
2 mm sheet, inside radius 4 mm240.4007.54064.4594
3 mm sheet, inside radius 3 mm330.3256.24395.7561
4 mm plate, inside radius 6 mm460.36911.7438.2566
6 mm plate, inside radius 9 mm690.36917.61512.385
8 mm plate, inside radius 12 mm8120.36923.48716.513
10 mm plate, inside radius 15 mm10150.36929.35920.641

Every row is worked out by this calculator each time the site is built, and checked for impossible values. Open a case to load its inputs.

Common mistakes

  • Entering the included angle as the bend angle. A drawing that shows 135° between the legs means a 45° bend. For the 30 × 50 × 30 mm channel of the example with two 45° bends the blank is 107.54 mm; entering 135° gives 83.86 mm, almost 24 mm short.
  • Adding the bend allowance to outside dimensions. Bend allowance goes with the flat lengths inside the bends; bend deduction goes with the outside dimensions. Adding 2 × 4.16 mm to the 110 mm of outside legs in the example gives 118.33 mm instead of 102.33 mm.
  • Using the punch radius in air bending. In air bending the inside radius follows the die opening, so the part may not get the punch radius. If the channel of the example really bends to 3 mm instead of 2 mm, the blank is 101.74 mm, not 102.33 mm, and a blank cut to the 2 mm figure makes the part about 0.6 mm oversize.
  • One K-factor for every radius. The K-factor rises with R/T: DIN 6935 gives 0.325 at R = T, 0.400 at R = 2T and 0.5 from R = 5T. A fixed K = 0.44 makes the 2 mm channel blank 103.05 mm, 0.72 mm longer than the DIN value. Check it with a test bend.
  • A flange shorter than the outside setback. A 2 mm sheet over a 2 mm radius has an outside setback of 4 mm, so a 3 mm leg has no flat left to bend against. The calculator warns about it; it often means the leg lengths were entered in the wrong units.

FAQ

What is bend allowance?

The length of the neutral axis through the bend. Add it to the straight flat parts of the legs to get the blank length.

What is the difference between bend allowance and bend deduction?

Bend allowance is added to the inside flat lengths. Bend deduction is subtracted from the outside dimensions. Both give the same blank.

What K-factor should I use?

Usually between 0.3 and 0.5. Small radii give lower values, large radii approach 0.5. The DIN 6935 formula and a test bend are the best starting points.

How do I find the K-factor from a test bend?

Bend a strip of known length, measure the legs, and work out the bend allowance that matches. Then solve BA = θ (R + K T) for K.

Is the bend angle the same as the included angle?

No. The bend angle is 180° minus the angle between the legs. A part that opens to 135° has a 45° bend.

How does the inside radius depend on the die?

In air bending, the inside radius is a fraction of the V-die opening, set by the material. Bottoming and coining press the radius of the punch into the part.

Related calculators

What this calculator is checked against

Before every release the calculator must reproduce each case below. The note under each case says where the expected answer comes from: a standard, a textbook, a published table, or a hand calculation shown in full.

  1. DIN 6935: K = 0.325 at R = T, 0.400 at R = 2T, 0.4997 just below R = 5T and 0.5 from 5TDIN 6935: k = 0.65 + 0.5 log10(R/T), K = k/2
  2. 2 mm sheet, R 2 mm, 90°, K 0.325: BA = 4.1626 mm, OSSB = 4 mm, BD = 3.8374 mm; channel 30/50/30 mm has a 102.33 mm blankBA = θ(R + KT), OSSB = tan(θ/2)(R + T), BD = 2 OSSB − BA (hand calculation)
  3. Consistency: the flat length equals the inside flat portions plus the bend allowances (L-bracket 2 × 1 in, 0.06 in sheet, R 0.06 in, K 0.44)Flat = Σ(leg − setbacks) + Σ BA, the same blank measured two ways
  4. Per-bend angles: a 45° bend has OSSB = tan 22.5° (R + T) and a smaller deduction than 90°; a 1° bend deducts under 1 % of a 90° bendBend geometry; limiting case θ → 0
  5. A 180° bend, a single leg, a bad number, a radius below 0.1 T with the DIN K-factor and a too-short leg are caughtBehaviour check: warnings and rejected inputs
  6. Worked example of the article: the calculator reproduces 0.325, 4.16 mm, 3.84 mm, 102.33 mm to the digits printedThe worked example on this page, to the digits printed

Assumptions and sources

Assumptions and limits

  • The neutral axis lies at K × T from the inside surface and keeps its length through the bend; the K-factor depends on material, tooling and R/T, so a test bend gives the best value.
  • The suggested K-factor uses the DIN 6935 correction factor k = 0.65 + 0.5 log10(R/T) for R/T below 5 and k = 1 above, with K = k/2: 0.325 at R = T and 0.5 from R = 5T.
  • Leg lengths are outside dimensions measured to the intersection of the outside surfaces (the mould lines); the flat length is their sum minus one bend deduction per bend.
  • The bend angle is the angle the sheet turns through (90° for an L), not the included angle between the legs; angles from just above 0° to just below 180° are allowed.
  • Thinning in the bend, springback and the press brake's actual inside radius are not modelled; in air bending the radius follows the die opening rather than the punch.

Sources

  • DIN 6935:2011 Cold bending of flat rolled steel products, correction factor k and neutral fibre position
  • Benson, S. D., Press Brake Technology: A Guide to Precision Sheet Metal Bending (SME, 1997): bend allowance, outside setback and bend deduction with the K-factor

Cite this calculator

Papandreou, C. (2026). Bend allowance calculator (sheet metal flat length). Engineering Bible. https://engineeringbible.com/manufacturing/bend-allowance/

Embed this calculator on your site

Copy this HTML into your page. The calculator stays free to use and links back here.

By Christos Papandreou. Updated . How the numbers are checked.